5238-E P-218
SECTION 8 LATHE AUTO-PROGRAMMING FUNCTION (LAP)
(3) Finish contour definition start G code
•
This code declares the start of finish contour definition.
•
The blocks following the G81 or G82 block and followed by the G80 block define the finish
contour.
•
G81 code: Longitudinal contour
G82 code: Transverse contour
(4) Finish contour definition blocks
•
Define the finish contour using the G00, G01, G02, and G03 codes.
•
The tool retraction path after the completion of machining varies depending on whether the
first block contains the G00 or G01 code.
•
The G00 code can be used only in the first block.
•
F: Feedrate in finishing
S: Spindle speed in finishing
•
E: Feedrate along contour in the high-speed bar turning cycle
•
F, S, and E commands are all modal.
(5) Contour definition end G code (G80)
This code declares the end of contour definition.
(6) Call for rough turning cycle
•
The rough turning cycle is started by calling the contour definition blocks starting with G86.
•
When the contour definition blocks start with G83, AP Mode V (bar turning cycle) is
selected. (LAP4 only)
•
When the finish contour definition blocks start with G81 or G82, the AP Mode II (copy
turning cycle) is selected.
(7) Call for finish turning cycle
•
The finish turning cycle is carried out by designating G87 and calling for the finish contour
definition blocks starting with G81 or G82.
