5238-E P-162
SECTION 7 FIXED CYCLES
8-22. Program Examples
LE33013R0300900520001
When drilling the four 15 mm dia. holes shown above, program as below using G181 for the drilling
cycle.
LE33013R0300900520002
Command point
Example 1:
ø15 hole
Tool No. : T0101
Program
zero
Tool
: ø15 drill
80
100
A
B
C
D
C270
C180
C0
C90
60
φ
120
φ
SB = 400 min
-1
N099
N100
N101
N102
N103
N104
N105
N106
N107
N108
N109
N110
G00
G094
G181
G180
G00
G95
X1000
X200
X60
X120
X60
X1000
X1000
Z150
Z75
(R-27)
Z1000
C0
C90
C180
C270
K48
F40
M05
M110
M15
T0101
SB=400
M146
M12
M109
M02
Continued from turning operation program
Both X and Z axes
are programmed.
The spindle (C-axis) indexes to the 0
°
position. After the drill is positioned at
X60 at the rapid feedrate, it starts
rotating in the leftward direction at
400 min-1.
The drill is positioned at Z102 at the
rapid feedrate.
The drill is fed to Z75 at 40 mm/min,
thereby drilling hole A.
The drill is returned to Z102 at the
rapid feedrate.
The spindle indexes to the 90
°
position.
After the drill is positioned at X120 at
the rapid feedrate, it drills hole B in th
same manner as N103.
After the spindle indexes to the 180
°
position, the same drilling cycle is
executed for hole C.
After the spindle indexes to the 270
°
position, the drill is positioned at X60
and then the same drilling cycle is
executed for hole D.
G180 cancels the fixed cycle mode.
