Fagor 8025 T CNC, Operating Manual

Page: 262 / 309

148 8025/8030 CNC PROGRAMMING MANUAL
Format b) CALL:
N4 (G25,G26,G27,G28,G29) N4.4.2.
N4 : Block number
G25,G26,G27,G28,G29 : Codes for different jumps
N4.4.2 > Number of repetitions
> Number of the last block to be executed
> Number of the block the jump is aimed at
When the CNC reads such a block it jumps to the block identified between the N and the
first decimal point. It then executes the section of the program between this block and the
one identified between the two decimal points as many times as set by the last number. This
last number can take a value within 0 and 99, unless it is programmed using a parameter
in which case the limits are 0 and 255.
If only N4.4 is written the CNC will assume N4.4.1.
When the execution of this section is finished the CNC goes to the block next to the one
in which G25 N4.4.2. was programmed.
Example:
N0 G00 X10
N5 Y20
N10 G01 X50 M3
N15 G00 Y0
N20 X0
N25 G25 N0.20.8
N30 M30
When block 25 is reached the CNC will jump to block 0 and will execute 8 times the section
N0-N20. On completion of this, it will go to block 30.