Fagor 8025 T CNC, Operating Manual

Page: 125 / 309

8025/8030 CNC PROGRAMMING MANUAL 11
6.2. TYPES OF MOVEMENT
6.2.1. G00. Positioning
The movements programmed following G00 are executed at rapid feedrate set during the
final adjustment of the machine by means of the machine-parameters.
There are two different ways of movement in G00, depending on the value applied to
P607(3) machine-parameter.
a) G00 path not controlled. P607(3)=0
The rapid feedrate value is independent for each axis, thus, the path is not controlled when
more than one axis move at the same time.
b) Vectored G00. P607(3)=1
When several axes move simultaneously, the resulting path is a straight line between the
initial and the final point. Feed will be set by the slowest axis.
a) P607(3)=0 b) P607(3)=1
When programming G00 function, the last F programmed is not cancelled, that means that
when G01,G02 or G03 is programmed again, the mentioned F is recovered.
In G00 movements, P4 machine-parameter can be used to identify whether the feedrate
override knob operates between 0% and 100% or is frozen at 100%.
The G00 code freezes the tool radius offset (G41, G42). I.e., when it is working with G41
or G42 and G00 is programmed, the radius offset remains ineffective until G01, G02 or
G03 is programmed again.
The code G00 is modal and incompatible with G01,G02,G03 and G33. G00 function can
be programmed with G or G0.