Fagor 8025 T CNC, Operating Manual

Page: 147 / 309

8025/8030 CNC PROGRAMMING MANUAL 33
6.8. G25. UNCONDITIONAL JUMP/CALL
The function G25 can be used to jump to another block of the current program.It is not
possible to program more information in the same block as the G25 function is program-
med. There are two possibilities:
Format a) N4 G25 N4
N4 - Block number
G25 - Code for unconditional jump
N4 - Number of the block the jump is aimed at
When the CNC reads this block, it jumps to the targeted block and the program continues.
Example:
N0 G00 X100
N5 Z50
N10 G25 N50
N15 X50
N20 Z70
N50 G01 X20
When the block 10 is reached, the CNC jumps to block 50 and then the program continues
until it is finished.
Format b) N4 G25 N4.4.2
N4 > Block number
G25 > Code unconditional jump
N4.4.2 > Number of repetitions
> Number of the last block to be executed
> Number of the block to which the jump is targeted
When the CNC reads such a block, it jumps to the block identified between the N and the
first decimal point. Then, it executes the section of the program between the mentioned
block and the one identified between the two decimal points as many times as set by the
last digit. This digit may have a value between 0 and 99, unless it is programmed by a
parameter, in which case the limits are 0 and 255. If only N4.4 is written, the CNC will
assume N4.4.1. When the execution of this section is finished the CNC goes to the block
after the one in which G25 N4.4.2 was programmed.