HEIDENHAIN TNC 620 E, User Manual

Page: 590 / 840

Multiple-Axis Machining | Running CAM programs
13
590
HEIDENHAIN | TNC 620 | Conversational Programming User's Manual | 10/2017
Consider with post processor configuration
Take the following points into account with post processor
configuration:
Always set the data output for axis positions to at least four
decimal places. This way you improve the quality of the NC data
and avoid rounding errors, which can result in defects visible to
the naked eye on the workpiece surface. Output to five decimal
places (option 23) may achieve improved surface quality for optical
components and components with very large radii (i.e. small
curvatures), for example forms for the automotive industry.
Always set the data output for the machining of surface normal
vectors (LN blocks, only Klartext conversational programming)
to a precision of seven decimal places, as LN blocks are always
calculated with a high accuracy, regardless of the setting of Option
23.
Set the tolerance in Cycle 32 so that in standard behavior it is at
least twice as large as the chord error defined in the CAM system
Also note the information in the functional description for Cycle
32.
If the chord error selected in the CAM program is too large,
then, depending on the respective curvature of a contour, large
distances between NC blocks can result, each with large changes
of direction. During machining this leads to drops in the feed rate
at the block transitions. Recurring and equal accelerations (i.e.
force excitation), caused by feed-rate drops in the heterogeneous
NC program, can lead to undesirable excitation of vibrations in the
machine structure.
You can also use arc blocks instead of linear blocks to connect the
path points calculated by the CAM system. The control internally
calculates circles more accurately than can be defined via the
input format
Do not output any intermediate points on exactly straight lines.
Intermediate points that are not exactly on a straight line can
result in defects visible to the naked eye on the workpiece surface
There should be exactly one NC data point at curvature transitions
(corners)
Avoid sequences of many short block paths. Short paths between
blocks are generated in the CAM system when there are large
curvature transitions with very small chord errors in effect. Exactly
straight lines do not require such short block paths, which are
often forced by the continuous output of points from the CAM
system
Avoid a perfectly even distribution of points over surfaces with
a uniform curvature, since this could result in patterns on the
workpiece surface
For 5-axis simultaneous programs: avoid the duplicated output of
positions if they only differ in the tool’s angle of inclination
Avoid the output of the feed rate in every NC block. This would
negatively influence the control’s velocity profile