Programming and Operating Manual (Milling)
110
6FC5398-4DP10-0BA1, 01/2014
Explanation
In block N10, the starting conditions are assigned to the corresponding arithmetic parameters. The calculation of the
coordinates in X and Z and the processing takes place in N20.
In block N30, R1 is incremented by the clearance angle R3, and R4 is decremented by 1.
If R4 > 0, N20 is executed again; otherwise, N50 with End of program.
8.14.4
Jump destination for program jumps
Functionality
A label or a block number serve to mark blocks as jump destinations for program jumps. Program jumps can be used to
branch to the program sequence.
Labels can be freely selected, but must contain a minimum of 2 and a maximum of 8 letters or numbers of which the first two
characters must be letters or underscore characters.
Labels that are in the block that serves as the jump destination are ended by a colon. They are always at the start of a block.
If a block number is also present, the label is located after the block number.
Labels must be unique within a program.
Programming example
N10 LABEL1: G1 X20 F100
;LABEL1 is the label, jump destination
N20 G0 X10 Y10
TR789: G0 X10 Z20
;TR789 is the label, jump destination
N30 G0 X30 Z30
- No block number existing
N100 G0 X40 Z40
;Block number can be jump target
M30
8.15
Subroutine technique
8.15.1
General information
Application
Basically, there is no difference between a main program and a subroutine.
Frequently recurring machining sequences are stored in subroutines, e.g. certain contour shapes. These subroutines are
called at the appropriate locations in the main program and then executed.
One form of a subroutine is the machining cycle. The machining cycles contain generally valid machining cases (e.g. drilling,
tapping, groove cutting, etc.). By assigning values via included transfer parameters, you can adapt the subroutine to your
specific application.
See the following illustration for example for using a subroutine for a workpiece four times:
