154
96-8000 Rev AC
May 2010
.
00011 ;
G59 ;
G00 G90 X0 Y0 Z0 ;
M98 P1 ;
G51 X1.0 Y1.0 P2 ;
M98 P1 ;
M30 ;
= Work coordinate origin
= Center of scaling
X
Z
Y
G51 Scaling
Programming notes:
Tool offsets and cutter compensation values are not affected by scaling.
Scaling does not affect canned cycle Z-axis movements such as clearance
planes and incremental values.
The final results of scaling are rounded to the lowest fractional value of the
variable being scaled.
G52 Set Work Coordinate System (Group 00 or 12)
The G52 command works differently depending on the value of setting 33. Set
-
ting 33 selects the Fanuc, Haas, or Yasnac style of coordinates.
If Yasnac is selected, G52 is a group 12 G-code. G52 works the same as G54,
G55, etc. All of the G52 values will not be set to zero (0) when powered on,
reset is pressed, at the end of the program, or by an M30. When using a G92
(Set Work Coordinate Systems Shift Value), in Yasnac format, the X, Y, Z, A,
and B values are subtracted from the current work position, and automatically
entered into the G52 work offset.
If Fanuc is selected, G52 is a group 00 G-code. This is a global work coor
-
dinate shift. The values entered into the G52 line of the work offset page are
added to all work offsets. All of the G52 values in the work offset page will be
set to zero (0) when powered on, reset is pressed, changing modes, at the end
of the program, by an M30, G92 or a G52 X0 Y0 Z0 A0 B0. When using a G92
(Set Work Coordinate Systems Shift Value), in Fanuc format, the current posi
-
tion in the current work coordinate system is shifted by the values of G92 (X, Y,
Z, A, and B). The values of the G92 work offset are the difference between the
current work offset and the shifted amount commanded by G92.
If Haas is selected, G52 is a group 00 G-code. This is a global work coordinate
shift. The values entered into the G52 line of the work offset page are added
to all work offsets. All of the G52 values will be set to zero (0) by a G92. When
using a G92 (Set Work Coordinate Systems Shift Value), in Haas format, the
current position in the current work coordinate system is shifted by the values
of G92 (X, Y, Z, A, and B). The values of the G92 work offset are the difference
between the current work offset and the shifted amount commanded by G92
Summary of Contents for 96-8000
Page 15: ...6 96 8000 Rev AC May 2010 Mill Warning Decals ...
Page 16: ...7 96 8000 Rev AC May 2010 Safety Lathe Warning Decals ...
Page 41: ...32 96 8000 Rev AC May 2010 ...
Page 93: ...84 96 8000 Rev AC May 2010 ...
Page 129: ...120 96 8000 Rev AC May 2010 ...
Page 133: ...124 96 8000 Rev AC May 2010 ...
Page 268: ......
Page 269: ......
