HEIDENHAIN 548431-05, Руководство пользователя, Страница: 383 / 722

Teach-in | Milling cycles
5
HEIDENHAIN | MANUALplus 620 | User's Manual | 12/2017
383
Face milling
Select
Milling
Select Face milling
Depending on the parameters, the cycle mills the following
contours on the face:
One or two surfaces ( Q = 1 or Q = 2, B > 0)
Rectangle (
Q
= 4,
L
<>
B
)
Square ( Q = 4, L = B )
Triangle or polygon ( Q = 3 or Q > 4, L <> 0)
Circle (
Q
= 0,
RE
> 0,
L
and
B
: no input)
Cycle parameters:
X , Z : Start point
C : Spindle angle – C-axis position (default: current spindle
angle)
X1
:
Dia. of figure center
C1 : Angle of figure center (default: Spindle angle C )
Z1 : Millg. top edge (default: Starting point Z )
Z2
:
Milling floor
Q : Number edges
Q
= 0: Circle
Q = 1: One surface
Q = 2: Two surfaces offset by 180°
Q
= 3: Triangle
Q = 4: Rectangle, square
Q > 4: Polygon
L
:
Edge length
Rectangle: Rectangle length
Square, polygon: Edge length
Polygon:
L
< 0 inscribed circle diameter
Circle: No input
B : Width/Width across flats
For Q = 1, Q = 2: Remaining thickness (remaining material)
Rectangle: Rectangle width
Square, polygon (
Q
>= 4): Width across flats (use only for
even number of surfaces; program "B" as an alternative to L )
Circle: No input
RE : Rounding radius (default: 0)
Polygon (
Q
> 2): Rounding radius
Circle ( Q = 0): Radius of circle
A : Angle to X axis (default: 0°)
Polygon (
Q
> 2): Position of figure
Circle: No input
T : Tool number – turret pocket number