Programming
10.5 Special functions
Cylindrical grinding
284
Programming and Operating Manual, 07/2009, 6FC5398-4CP10-2BA0
Deactivate constant cutting rate: G97
The function "Constant cutting rate" is deactivated with G97. If G97 is active, a programmed
S word is given in RPM as the spindle speed .
If no new S word is programmed, the spindle turns at the last defined speed with G96
function active.
Programming example
N10 ... M3
; Spindle's direction of rotation
N20 G96 S120 LIMS=2500
; Activate constant cutting speed, 120 m/min, speed
limit 2,500 r.p.m.
N30 G0 X150
; no change in speed, because block N31 with G0
N31 X50 Z...
; no change in speed, because block N32 with G0
N32 X40
; Approach on contour, new speed is automatically set as
is required for the beginning of block N40
N40 G1 F0.2 X32 Z...
; Feedrate 0.2 mm/
revolution
...
N180 G97 X... Z...
; Deactivating constant cutting rate
N190 S...
; new spindle speed, r.p.m.
Information
The G96 function can also be deactivated with G94 or G95 (same G group). In this case, the
last programmed spindle speed S is active for the remaining machining sequence if no new
S word is programmed.
The programmable offset TRANS or ATRANS (see section of that name) should not be used
on the transverse axis X or used only with low values. The workpiece zero point should be
located at the turning center. Only then is the exact function of G96 guaranteed.