Fagor 8025 GP, Руководство по эксплуатации

Страница: 272 / 423

152 8025/8030 CNC PROGRAMMING MANUAL
6.32.2. Cancellation of canned cycles .
Programming the code G80 in a block cancels any canned cycle that is active.
. When a canned cycle is defined, it cancels and replaces any others that are active.
. Canned cycles are also cancelled by means of MO2, M30, RESET or EMERGENCY.
. All canned cycles except G79 are also cancelled by G32, G53/G59, G74, G92, M02, M30,
RESET or EMERGENCY or when a new main plane has been selected with G17, G18 or
G19.
6.32.3. General considerations
. A canned cycle can be defined within a standard or parametric subroutine.
. Calling of standard or parametric subroutines can be performed from a block of the zone of
influence of a canned cycle without involving cancellation of the canned cycle.
. The performance of the canned cycle does not affect the sequence of the preceding G
functions or the direction of rotation of the spindle. A canned cycle may begin with either
direction of rotation (M03,M04) and end with the same direction (this is not affected by the
stops and reversal involved in the cycle).
. If the canned cycle begins with the spindle not running, the latter starts clockwise (M03) and
continues rotating clockwise on completing the cycle.
. Defining a canned cycle cancels radius compensation. It is equivalent to G40.
. The execution of a canned cycle alters the value of the Arithmetic parameters P70 to P99.
. In the block of definition of a canned cycle, the cycle relevant G will be cancelled if after
it, G02,G03,G08,G09 or G33 (one of them) is programmed.
. When defining a canned cycle, except G79, either while functions G02,G03 or G33 are
active or programming functions G08 or G09 in the same block, the CNC will display error
4.
. Once a canned cycle has been defined, the functions G02,G03,G08 or G09 can be
programmed in the subsequent blocks.