Fagor CNC 8058elite T, Руководство пользователя

Страница: 35 / 90

CNCelite
8058 8060
8065
2
ꞏ35ꞏ
R
EF
. 2106
2.
PROBING.
2.1 G100/G103. Probing.
With function G100, it is possible to program movements that will end when the CNC receives
the probe signal (when the probe makes contact) or when the probe reaches the
programmed position. When done probing, the CNC assumes as the theoretical position the
current position of the axes involved in the movement, their real (actual) position at that
instant.
With function G103, it is possible to program movements that will end when the CNC stops
receiving the probe signal (when the probe stops making contact) or when the probe reaches
the programmed position. When done probing, the CNC assumes as the theoretical position
the current position of the axes involved in the movement, their real (actual) position at that
instant.
Functions G100 and G103 do not execute the tool change to select the probe, the probe must
be selected in a previous block of the program. Likewise, when using more than one probe,
the probe to be used must be selected before probing.
Probing programming.
The probing movement is defined using function G100 or G103 followed by the coordinates
of the probe's target point. Programming the feedrate is optional; if not programmed, these
movements are carried out at the active feedrate.
Programming format.
The programming format is: Optional parameters are indicated between angle brackets.
G100 X..C <F>
G103 X..C <F>
Probing feedrate.
The CNC uses the same feedrate for probing and for machining. The feedrate "F" set for
the probe will be the feedrate active at the CNC when done probing.
The maximum probing feedrate in each axis will be limited by machine parameter
PROBEFEED and this value will not be exceeded even when programming a higher value
or exceeded with the switch on the operator panel.
The active feedrate may be varied between 0% and 200% using the selector switch on the
CNC's operator panel or it may be selected by program or by PLC.
X..C Coordinates of the probing point.
F Optional. Feedrate.
If not programmed, the CNC uses the active feedrate.
G100 X45.23 Z23.45
G100 Z50 F100
G103 X2.6 Z3 F20
G103 Z1 F20